MechMate CNC Router Forum

Go Back   MechMate CNC Router Forum > Personal Build Histories > MechMates already cutting
Register Options Profile Last 1 | 3 | 7 Days Search Today's Posts Mark Forums Read

Reply
 
Thread Tools
  #1  
Old Wed 30 March 2016, 05:17
james burrus
Just call me: james
 
new jersey
United States of America
Can you do 2- z axis

I was worried can you have a machine with 2Z axis One for drilling 5 mm holes and one for cutting. I think about a 5 x 10 cutting area
Reply With Quote
  #2  
Old Wed 30 March 2016, 10:57
darren salyer
Just call me: Darren #101
 
Wentzville mo
United States of America
There is someone here who has, I believe.
Room for dust collection becomes a problem, if I remember correctly.
Reply With Quote
  #3  
Old Wed 30 March 2016, 13:27
smreish
Just call me: Sean - #5, 28, 58 and others
 
Orlando, Florida
United States of America
Yes, yes I have.
Dust collection had to be reduced to a 2-1/2 hose, but in the y-car bay i had:
1) Porter Cable 7518 router on extended z axis
1) Standard z-spider with air drill mounted as far off center line as possible to make room for dust collection.

I don't have pictures, it was a limited specialty use years ago, but the y-car is designed large enough to hold 2 spiders back to back
Reply With Quote
  #4  
Old Thu 31 March 2016, 03:28
Alan_c
Just call me: Alan (#11)
 
Cape Town (Western Cape)
South Africa
Send a message via Skype™ to Alan_c
On this matter Sean, how did you make the software play nicely with two Z-axes? In the CAM program and in Mach3?
Reply With Quote
  #5  
Old Thu 31 March 2016, 10:36
smreish
Just call me: Sean - #5, 28, 58 and others
 
Orlando, Florida
United States of America
dual z axis machine workarounds

Alan,
I did a really crude work around in the two different times I did it.

1) I did two individual tool path files and ran the air drill Z axis with that AXIS plugged in to the SINGLE wire feed for that stepper, then just quickly re-patched to the spindle z on the second pass. This is all due to the fact that Mach 3 does not support more than 1 z axis. THIS USES two (1) stepper motor per z axis for a total of two on the machine and using ONE driver in the cabinet.

2) the best solution so far has been on the second z, I just used an air cylinder with hard stops to manually adjust the depth to drill and used the relay out on the PMDX board to "fire and drill" and the appropriate times, which allows for only 1 tool path profile, but a longer set up time for the machine. I my case, I was only using it for 5mm drill and a 7mm depth, so it as an easy accessory. THIS USES two (1) stepper motor per z axis and one AIR Solenoid activated by the PMDX on a fixed stroke and retraction cycle determined by hard stops. (I'm going to find the link and add shortly of the video I used for support)

3) option that I did briefly is the following:

You can set up a macro to swap the axis. Say your drill is the B axis.


In the macro, put

SwapAxis(2,4)

and call it before driling and Z commands will now move the drill.

After drilling, call another macro with

ResetAxisSwap()

I'd recommend using one offset for routing and another for drilling. So if you use G54 when routing, you need to call G55 when you do the SwapAxis. The G55 would contain the offset info from the router to the drill. And when switching back, call G54.

One issue you might have is if you use the Zero axis buttons, you'll be changing the G54 or G55 values, which you don't want to do.

You're going to have to learn to write simple macros to do this.

Last edited by smreish; Thu 31 March 2016 at 10:47..
Reply With Quote
  #6  
Old Fri 01 April 2016, 15:48
danilom
Just call me: Danilo #64
 
Novi Sad
Serbia
You can use this script which moves all tool number 2 moves to other axis than Z, just be carefull not to load the modified code twice and parse it. I made two buttons ... simple LOAD and LOAD dual spindle code to the screen

http://www.machsupport.com/forum/ind...html#msg159843

thats how I would do it and did on this machine

http://www.mechmate.com/forums/showt...ghlight=skopje

VIDEO
Reply With Quote
Reply

Register Options Profile Last 1 | 3 | 7 Days Search Today's Posts Mark Forums Read

Thread Tools

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off

Forum Jump

Similar Threads
Thread Thread Starter Forum Replies Last Post
Setting the Y-axis square to the X-axis Gerald_D 20. Gantry 10 Fri 12 October 2012 01:44
Setting A-axis terminal as X2-axis in EMC2 KenC CNC motion control software 2 Wed 27 January 2010 06:40
Rotary axis (4th Axis) or Indexer software smreish Graphics & CAD 0 Tue 28 July 2009 07:02
Longer Z Axis or 5 Axis Hovernut Archives 31 Sat 25 October 2008 16:56


All times are GMT -6. The time now is 15:18.


Powered by vBulletin® Version 3.8.3
Copyright ©2000 - 2019, Jelsoft Enterprises Ltd.